SetToFaceExtent does not seem to work for HoleFeature

By Philippe Leefsma

Q:

When I try to use SetToFaceExtent on a HoleFeature, then it keeps returning error. What shall I do?

A:

This is as designed. To set the Face – which is a BRep input – to the Hole Feature, the stop node has to be moved above the Hole Feature. This is required for any Feature edit that involves a BRep input. On moving the stop node above the Hole Feature the call to SetToFaceExtent succeeds even with a Face as input.

    Sub SetToFaceExtentTest(ByVal app As Inventor.Application)

        Try

            Dim doc As PartDocument = app.ActiveDocument

            Dim hf As HoleFeature = app.CommandManager.Pick(

                SelectionFilterEnum.kPartFeatureFilter,

                "Select hole feature:")

            If hf Is Nothing Then

                Return

            End If

            Dim face As Face = app.CommandManager.Pick(

                SelectionFilterEnum.kPartFacePlanarFilter,

                "Select planar face:")

            If face Is Nothing Then

                Return

            End If

            hf.SetEndOfPart(True)

            hf.SetToFaceExtent(face, True)

            doc.ComponentDefinition.SetEndOfPartToTopOrBottom(False)

        Catch ex As Exception

            MsgBox(ex.ToString())

        End Try

    End Sub

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